Add a Custom Command for Header Lines for Post Processing in NX 9 CAM

Follow these simple steps to create a Custom Command in NX CAM to add to a post processor for header lines to be output from a post processor:

Start Postbuilder.

Select the custom command tab.

Select the Create option.

Right mouse button on the new custom command and rename it. To PB_CMD_header line.

Highlight everything in the right window, as displayed below.

Once everything is highlighted, select the delete key.

Select the lines below:

#=============================================================
proc PB_CMD_header_line { } {
#=============================================================
#This Custom Command will output the header information

#this will output information associated with a program

global mom_oper_program
global mom_part_name
global mom_date
global mom_logname

MOM_output_literal "(PROGRAM NUMBER: $mom_oper_program)"
MOM_output_literal "(PART NAME : $mom_part_name)"
MOM_output_literal "(POSTED DATE : $mom_date)"
MOM_output_literal "(PROGRAMMED BY : $mom_logname)"}

Copy the lines selected above and paste them into the right side of the dialog box. It should appear like this:

Select the Program Tab.

Select the Program Start Sequence.

Select the name of the custom command you just created. In this case it should be the  PB_CMD_header line.

Select the Add block option.

Drag the command after the rewind stop code.

This will add the header lines to the beginning of the CNC program.

Want to learn more about customizing your posts? Get training in NX CAM post processing from Swoosh Technologies. Learn more here!

Written by
Brian Brown
Application Engineer
Swoosh Technologies

NX CAM Tips & Tricks: Coolant Thru Custom Command

Follow these steps to create a simple custom command to add to a post processor. This will allow you to utilize the coolant thru switch on the tool description dialog box in NX CAM.

Start Postbuilder.

Select the custom command tab.

Select the Create option.

Right mouse button on the new custom command and rename it. To PB_CMD_coolant_thru.

Highlight everything in the right window, as shown below:

Once every thing is highlight, select the delete key!

Select the lines below:

#=============================================================
proc PB_CMD_coolant_thru { } {
#=============================================================
global mom_tool_coolant_through
global mom_coolant_status
if { [ info exists mom_tool_coolant_through ]  } {
  if { $mom_tool_coolant_through == "Yes" } {
     set mom_coolant_status "THRU"
     }
   }
}
}

Copy the lines selected above and paste the lines into the right side of the dialog. It should appear as follows:

Select the Program Tab.

Select the Operation Start Sequence.

Under the Initial Move block.

Select add a new block.

Select the coolant thru command you just created from the drop menu.

Your coolant thru on the tool dialog box is now ready to use!




Learn more about customization in NX CAM with training from Swoosh Technologies. See the full training schedule here.

Brain Brown
Application Engineer
Swoosh Technologies